emcPT wrote: 1) One year ago, calling a tools in a lathe had a syntax different from the Fanucs, okumas, ..., that I really like. T0405 for example. It was necessary to use a D word. I also remember that the tool data table was hard to figure out as it was initial made for milling. From what I remember to read this is now implemented. Can it be confirmed?
There was a change made to the development branch (normally called "master", sometimes 2.6) that allowed this syntax for a tool change.
It does not have universal support, as there is some unease about having two such very different behaviours in the same software. It might not make it into a released version.
An alternative to the Daniel Rogge patch would be to use the G-code remapping option.
www.linuxcnc.org/docs/devel/html/remap/structure.html
This would let you re-define T1122 into M6T11G43H22 (for example). If you are re-mapping then I _think_ it might be possible to also use the U/W offsets in the tool table as wear offsets.
Note that the tool table editor now allows you to not display irrelevant columns.
If there is enough support for the idea it is possible that the T1122 tool change format might be turned on simply by the LATHE=1 line in the INI.
2) The lathe that I will retrofit have the tools upside the Z zero (far away from the user). This is the most usual in cnc lathes, I think. I remember that in axis it was not possible to see the tools like that, and they would be seen in reverse. What is the current status?
There is a workaround for this using coordinate system rotation. I haven't tried it, but at least one chap seemed happy with it as a solution.
3) Although not very important to me to use the live tooling, it would be a waist to let them go. It would value a lot the machine and will make it more versatile. Anyone knows about someone that is using them on a lathe? I understand that this will imply a lot about the spindle and so on, but I was wondering if this was already addressed.
It would be very easy to control live tooling with user-defined M-codes for example. M103 P1000 for clockwise at 1000 rpm.
www.linuxcnc.org/docs/2.5/html/gcode/m-c...tml#sec:M100-to-M199
4) I also remember that changing something on the visual looks of the axis front end was something that was hard. It is still hard?
Yes. Axis is still hard. However it is entirely possible to create your own GUI from scratch (though it is a lot of work). Alternatively Chris' "GScreen" GUI is written in Glade and can be easily modified.
5) Cycles. Mainly the G71 G72 G73 (in respect to the Fanuc) . They were not implemented one year ago, but I read a discussion where it seams to be already implemented. True or false?
Not implemented. I don't know what happened to that work. Again they _could_ be added with the remapping technique mentioned earlier.
